CNC Machining of Deep Cavity Housings

• 1
  Why cavity depth is the hardest number on the drawing
• 2
  Tool selection and reach limits inside a closed cavity
• 3
  Wall deflection, floor thickness and heat in thin housing walls
• 4
  How many setups a deep cavity housing really needs
• 5
  When deep cavity housings should not be milled
• 6
  Step by step: machining a deep cavity housing
• 7
  Depth-to-diameter guide for cavity housings

A cavity housing is any part where the pocket depth is large relative to the opening. Gearbox cases, sensor housings, valve bodies, camera enclosures, pump bodies. The drawing usually shows a wall thickness, a floor thickness, a corner radius and a depth. What it does not show is how much the tool will bend at that depth, and that is the number that decides whether the part is machinable on a milling center at all.

The controlling ratio is depth to cutter diameter, written as L:D. A 10 mm end mill reaching 50 mm deep runs at 5:1. That is routine. At 8:1 the tool starts to push off the wall under cutting load, and the finished cavity comes out tapered or bell-mouthed even if the machine is accurate. Past 10:1 most solid carbide end mills need a neck relief, which reduces stiffness further, and the achievable tolerance loosens fast.

Chip evacuation matters just as much as stiffness. In a deep closed pocket, chips pile at the bottom and get re-cut. Re-cut chips double the cutting load at the tip and generate heat that dulls the corner radius. The usual fix is through-spindle coolant or air blast aimed at the floor, plus pecking cycles that lift the tool clear often enough to clear the pocket.

So the first engineering question is not which machine to use. It is whether the cavity can be reached, cleared and measured at the required tolerance while it is still one solid piece of metal.

• 1
  Rough ruleUnder 5:1 L:D, standard tooling and standard feeds apply.
• 2
  Caution zone5:1 to 8:1 needs reduced radial engagement and a necked tool.
• 3
  ReconsiderBeyond 10:1, expect taper, chatter or a design change.

A long tool is a spring. Deflection scales with the cube of the unsupported length, so a cutter that sticks out 80 mm instead of 40 mm is roughly eight times softer in bending. That is why deep cavity work uses reduced radial engagement rather than heavy passes. We typically cut radial width of cut at 3 to 6 percent of tool diameter and step down 0.2 to 0.5 mm on finishing passes in hard materials, trading metal removal rate for dimensional control.

Corner radii drive the whole plan. The smallest internal corner sets the largest tool that will fit, and the depth then sets the L:D ratio. A cavity 60 mm deep with a 4 mm corner radius forces a 4 mm cutter at 15:1, which is not a milling problem you can fix with feeds and speeds. Options are to open the corner radius, to relieve the neck, or to move that corner to EDM.

Helical and trochoidal toolpaths help more in deep pockets than in shallow ones. A trochoidal path keeps the engagement angle roughly constant, which keeps the side load on a long tool predictable instead of spiking at each corner. The floor can be finished with a smaller stepover; the walls are best finished in a single continuous spiral to avoid witness lines that show up after anodizing.

Material choice shifts the numbers. Aluminium 6061 and 7075 tolerate longer reach because cutting forces are low. Stainless 316 and 17-4PH work-harden, so a long tool that rubs instead of cuts will destroy itself in one pass. Titanium TC4 and Inconel need even shorter reach, lower surface speed and more coolant.

• 1
  Necked end millsShank diameter larger than cutting diameter for stiffness.
• 2
  Indexable long-reach headsBetter for roughing pockets above 6:1 in aluminium.
• 3
  Lollipop cuttersReach undercut shoulders and re-entrant features.

A deep cavity housing is usually a thin-walled box with a thick floor, or the reverse. Both distort. When the tool pushes on a 2 mm wall, the wall deflects away and springs back after the pass, leaving an oversized pocket and a wavy surface. The amount depends on wall height, unsupported length and cutting force, and it can be 0.05 mm or more on a tall housing.

The standard countermeasures are to leave more material for the finishing pass, to support the wall from the outside with fixturing or a soft-jaw cradle, and to take the final wall pass with a sharp, low-rake tool at light load. On very tall thin walls, we sometimes rough both sides symmetrically so the residual stress releases evenly instead of bowing the part one way.

Residual stress from the raw stock is a separate problem. A 7075 plate that has been cold-rolled will move when 70 percent of it is machined away. Stress-relieved stock or a rough-machine, stress-relieve, finish sequence costs more but holds flatness on a large housing. For a 4,000 mm part, that sequencing is often the difference between a usable housing and scrap.

Heat is the third input. Deep pockets trap heat because the chips and coolant cannot leave quickly. Thermal growth of 0.02 to 0.03 mm on a 200 mm aluminium housing is normal during a long roughing cycle, so final dimensions should be cut after the part has cooled, not immediately after roughing.

• 1
  Symmetric roughingBalance material removal on both walls.
• 2
  Soft jaws and cradlesSupport the wall instead of clamping the top edge.
• 3
  Cool before finishLet the housing return to room temperature first.

Every setup adds a datum error. A housing machined in three setups can accumulate 0.03 mm of positional error between the cavity and the mounting face even if each setup is individually accurate. The way to control this is to reduce setups, not to tighten each one.

A 3-axis machine can reach a cavity from one direction. Any cross-hole, side port or angled face then needs a second or third setup. A 5-axis machine with a Ø400 mm rotary table can often reach the cavity, the side ports and the mounting face in one or two setups by tilting the part. That is the main reason deep cavity housings show up in 5-axis work.

For parts that must stay on one datum, a mill-turn center is a strong option. Turning the outside diameter and boring the cavity on the same spindle removes concentricity error entirely. This suits cylindrical housings such as motor cans and pump bodies, where the bore and the outer register share an axis.

When the part is too large for a rotary table, the practical route is a large-travel 3-axis machine with a tombstone or angle plate, plus a probe to re-establish the datum between setups. GreatLight machines up to 4,000 mm and uses in-process probing to verify the cavity position before the finishing pass.

• 1
  One setupBest accuracy, limited feature access.
• 2
  Two setupsCommon for housings with side ports.
• 3
  Three or moreDatum error compounds; probe between setups.

Milling is the default because it produces a single piece with no joint. It stops being the right answer when the cavity is too narrow, too deep or too sharp-cornered for any tool that fits. At that point the choice is between changing the design and changing the process.

EDM, either wire or sinker, reaches corners a cutter cannot. A sinker electrode can burn a 1 mm internal radius at 30 mm depth with no tool deflection at all. The trade-offs are speed and cost: sinker EDM is far slower than milling and needs an electrode, so it is normally used only for the last few millimeters of depth or for the sharp corners after milling has removed most of the material.

Design changes are often cheaper than process changes. Increasing an internal corner radius from 3 mm to 6 mm can turn an 8:1 problem into a 4:1 problem with no loss of function. Splitting the housing into a body and a cover moves the cavity to an open pocket, which is faster, more accurate and easier to inspect. Casting or die casting the rough cavity and machining only the critical faces is another route for higher volumes.

For plastics and prototypes, the same geometry may be better served by 3D printing or vacuum casting, where depth creates no tooling problem at all. The decision hinges on quantity, tolerance and material, not on habit.

• 1
  Wire EDMThrough-cavities with sharp corners, limited to straight walls.
• 2
  Sinker EDMBlind cavities and sharp internal radii.
• 3
  Split designOpen pockets instead of deep ones; add a joint.