CNC Copper Processing Guide

• 1
  Key takeaways
• 2
  Why copper behaves differently at the cutting edge
• 3
  Tool geometry and coating choices that cut copper cleanly
• 4
  Speeds, feeds and depth of cut in practice
• 5
  Holding soft parts without distorting them
• 6
  Copper and brass grades: what each one is good for
• 7
  Symptom, cause and fix on copper parts

Copper is soft but not free-cutting. The chip forms by ductile shear, and for a brief window the built-up edge sits on the rake face, then breaks off. Each break takes a small piece of the machined surface with it. That is why a copper face can measure in tolerance and still show a torn, matte patch a few millimeters away.

Thermal conductivity around 390 W/m·K in C110 means heat does not stay at the tool tip. It flows into the workpiece, the fixture and the chip. The cutting zone stays cool, so tool life is long, but the part grows. A 200 mm copper plate can move 0.05 mm or more between a cold morning and a warm afternoon, which is ten times the tolerance we hold.

Ductility is the third factor. Copper elongates before it fractures, so a chip that is too thin does not break. It folds, rubs and burnishes the surface it just left. Feed per tooth is the control knob here, not spindle speed. Too light a chip is the most common mistake on copper, and it shows up as a shiny, hard-to-measure surface.

Finally, copper work-hardens. Each pass raises the hardness of the layer below the cut. If the finishing pass removes material that was already deformed by a roughing pass, the tool meets a harder skin than the drawing suggests. Rough, then semi-finish, then finish with a real depth of cut for each.

• 1
  Built-up edge tears the surfaceIt forms and sheds repeatedly during the cut.
• 2
  Heat goes into the partMeasure after the part has cooled, not right after the cycle.
• 3
  A thin chip burnishesRaise feed per tooth before you raise spindle speed.
• 4
  Work hardening stacks upLeave enough stock for the finishing pass to cut, not rub.

Uncoated, polished carbide is the default. Copper does not need the hardness of a TiAlN or AlCrN layer, and those coatings are typically applied with a rougher surface that gives the chip something to grab. A polished rake face lets the chip slide. If you must use a coated tool, choose a thin, smooth coating and a fine-grain substrate rather than a thick multilayer.

Rake angle matters more than grade. A positive rake of roughly 10 to 15 degrees lowers cutting force and pulls the chip away from the workpiece. Negative rake tools, which work well in hardened steel, push the material ahead of the edge and make built-up edge worse on copper. For turning inserts, look for an aluminum-style geometry with a sharp, honed-but-not-rounded edge.

Diamond is the exception. Polycrystalline diamond tools hold an edge far longer in abrasive beryllium copper and in long runs of C110. The cost only makes sense when tool changes interrupt the cycle or when dimensional drift from edge wear is a real risk. For a 50-piece job, carbide wins on price.

For drilling, use a 130 to 140 degree point with polished flutes and a high helix. Copper chips are long and want an open path out of the hole. A slow spiral flute drill will pack the hole, raise torque and snap. Peck drilling helps on depths beyond three times the diameter.

• 1
  Polished uncoated carbide firstCoatings add friction on gummy material.
• 2
  Positive rake, sharp edge10 to 15 degrees lowers force and lifts the chip.
• 3
  PCD for long or abrasive runsJustified by tool life, not by finish alone.
• 4
  High-helix drillsGive long copper chips a way out of the hole.

Surface speed for copper in carbide runs from about 150 to 300 m/min, higher than for mild steel and lower than the 500 m/min plus you might use on 6061 aluminum. The exact number matters less than the feed per tooth. For a 10 mm end mill, aim for 0.05 to 0.12 mm per tooth. Below about 0.03 mm per tooth the edge rubs and the surface burnishes.

Radial engagement should stay modest. A 30 to 40 percent stepover on roughing keeps the chip load up and the heat down. Full-width cuts in copper tend to chatter because the material is soft and the tool is stiff, so the system rings instead of cutting. Trochoidal or dynamic paths work well here because they keep the chip thickness constant while limiting engagement.

Axial depth can be more aggressive than you might expect. Because the material is soft, a 1× to 2× diameter axial cut is common on roughing with a rigid setup. The limit is usually chip evacuation, not cutting force. Flood coolant or high-pressure through-tool coolant clears the long chips and stops them from being recut, which is where most surface damage comes from.

For finishing, take a real depth of cut, typically 0.2 to 0.5 mm radially. A spring pass at the same setting removes the elastic recovery left by the previous pass. Copper springs back more than steel after the edge passes, so a nominal 0.1 mm finish cut may leave the wall slightly oversize if the tool deflects.

• 1
  Start at 0.05–0.12 mm per toothBelow 0.03 mm per tooth, the edge rubs.
• 2
  30–40 percent stepover on roughingKeeps chip load high and chatter low.
• 3
  Through-tool coolantClears long chips before they are recut.
• 4
  Spring pass on finishingRecovers the elastic springback copper leaves behind.

Copper dents under clamping pressure. A vise tightened to the same torque you would use on 4140 will leave marks and, on thin walls, a permanent bow. Use soft jaws machined to the part profile, or a fixture plate with more, smaller clamps rather than fewer strong ones. For thin plates, vacuum fixturing spreads the load across the whole face.

Thin-wall turning needs support as well. A steady rest or a tailstock helps, but the bigger gain comes from cutting the wall in stages and letting the part relax between passes. Copper stress-relieves at low temperature, so an anneal between roughing and finishing removes the residual stress that would otherwise pull the bore out of round after the part leaves the machine.

Deburring is not optional. Copper burrs are ductile and roll over rather than break off, so a hand file pushes them into the edge instead of removing them. A controlled edge break with a chamfer tool in the cycle, followed by vibratory tumbling, gives a repeatable result. Hand deburring on a 500-piece run will not hold consistency.

Inspection has to account for temperature. A part measured hot off the machine can read undersize and grow back into tolerance as it cools. Let parts stabilize, or measure at a controlled temperature, before you decide a dimension is wrong.

• 1
  Soft jaws, more clampsDistribute force instead of concentrating it.
• 2
  Relax between passesLet the part move before the finishing cut.
• 3
  Chamfer in the cycleCopper burrs roll over rather than break.
• 4
  Measure after coolingThermal growth is larger than the tolerance band.