Methods for improving the process of CNC machining of thin-walled parts
Thin walls fail for predictable reasons: cutting force pushes the wall, heat moves it, and the fixture lets it spring back. This guide is for engineers who own the process and need a plan they can run on the floor. You will get fixture rules, toolpath choices, parameter ranges, and the checks that catch a problem before the finishing pass.
In this article
- 1
- 2
- 3
- 4
- 5
- 6
- 7
- 8
Key takeaways
Where CNC machining of thin-walled parts goes wrong
A thin wall is a spring. When the cutter pushes on it, the wall bends away, the chip load drops, and the tool rubs instead of cutting. The moment the tool passes, the wall springs back and cuts oversize. Then the finishing pass removes uneven stock and the wall moves again. That is why two identical parts can measure differently after the same program.
Heat is the second problem. A wall under 1 mm thick has little material to soak up heat, so the wall grows while cutting and shrinks after cooling. On aluminium, a 60 mm long wall can move 0.02–0.04 mm from thermal growth alone. On stainless and titanium the effect is smaller but the cutting forces are higher, so deflection dominates.
The third problem is the fixture. Most thin-wall jobs are held on a vise or a plate with clamps at the ends. The middle of the wall is unsupported, and that is exactly where the cutter spends most of its time. Improving the process of CNC machining of thin-walled parts starts with fixing support, not with slowing the spindle down.
Residual stress in the raw stock matters too. A 7075 plate that has been rolled and not stress-relieved will move after the first heavy cut, whether the wall is 0.8 mm or 3 mm. For walls under 1.5 mm, ask for stress-relieved stock or plan a stress-relief pass before finishing.
Support the wall before you cut it
The single biggest gain comes from keeping material behind the wall until the last operation. Machine the pocket from both sides and leave a sacrificial web, or leave the wall at 2–3 mm and bring it to final thickness in a separate light pass. The wall never sees a heavy cut at final thickness.
When the geometry allows it, fill the pocket with a low-melt wax or a machinable support resin. The filler takes the radial load and the wall stays straight. This works well on housings with a closed pocket and on parts where the wall is longer than 4× its thickness.
For open walls, use a tailstock or a dedicated soft jaw that matches the wall profile. A jaw that contacts the wall along 70–80% of its length is far better than three point contacts. Torque the clamps evenly; uneven clamping bends the part before the first cut and the error shows up in the final dimension.
Vacuum fixturing is a good option for thin plates. A 0.5 mm plate held on a vacuum table with a proper gasket seal will not lift under a light finishing cut. Keep the vacuum area as large as the part footprint and avoid small islands that leak.
- 1Leave a webKeep 2–3 mm of stock behind the wall until the final operation.
- 2Fill the pocketWax or machinable resin absorbs radial force on closed pockets.
- 3Match the jawSoft jaws profiled to the wall spread clamping load.
- 4Even clamp torqueUneven clamping bends the part before cutting starts.
Toolpath strategies that reduce wall deflection
Use climb milling on the wall. Climb milling pushes the tool into the material and the reaction force goes into the support side, not into the free wall. Conventional milling pulls the wall toward the cutter and makes deflection worse. On a 1 mm wall in 6061, switching to climb milling alone can cut wall movement by roughly half.
Cut the wall in a single continuous pass where possible. Stopping and restarting leaves a witness mark and a local stress concentration. If the wall is long, use a trochoidal or dynamic path with a constant radial engagement of 5–10% of the tool diameter. This keeps the force steady and avoids the spike that happens when the tool enters a full-width cut.
Do not finish the wall before the floor and the surrounding features are done. Every later cut releases stress and moves the wall. Sequence the job so the wall is the last feature machined, and keep the finishing allowance small and uniform.
For deep walls, use a tool with a short flute length and a reduced neck. A long, thin end mill deflects more than the wall does. A 6 mm cutter with a 20 mm flute length and a 4 mm neck will reach a 30 mm deep wall with less tool deflection than a standard 6 mm end mill.
Feeds, speeds, and coolant for wall stability
On aluminium 6061 with a 1 mm wall, run the finishing pass at 8,000–12,000 rpm with a 6 mm three-flute end mill, 0.02–0.05 mm/tooth, and a 0.05–0.10 mm radial depth. The low radial engagement keeps the radial force small, which is what the wall cares about. Axial depth can be larger, 0.15–0.25 mm, because it does not push the wall sideways.
On stainless 304 and 316, drop the speed to 2,500–4,000 rpm and use a four-flute cutter with a 0.03–0.06 mm/tooth feed. Stainless work-hardens, so never let the tool rub. If the wall starts to squeal, increase the feed per tooth rather than reducing it, and reduce the radial depth instead.
On titanium Ti-6Al-4V, use 800–1,200 rpm, 0.04–0.08 mm/tooth, and flood coolant. Titanium conducts heat poorly, so the wall heats up and grows. Check the wall with a micrometer after it cools, not while it is warm.
Air blast is often better than flood coolant on thin aluminium walls. Flood coolant creates a thermal gradient across the wall and can warp it. Air blast clears the chips and keeps the temperature more even. Use a mist if chip evacuation is a problem on deep pockets.
How to measure thin walls without chasing your tail
Measure the wall while the part is still clamped in the same setup that machined it. If you unclamp first, the wall relaxes and you cannot tell whether the error came from the cut or from the release of clamping stress. Take the reading, correct if needed, then unclamp and measure again.
Use a micrometer with a light friction thimble, not a caliper. A caliper jaw puts a point load on a thin wall and reads low. On a 0.8 mm wall in aluminium, a caliper can read 0.03–0.05 mm under the true thickness. A micrometer with a 6 mm anvil face spreads the load and gives a repeatable number.
For long walls, measure at five points along the length: both ends, the middle, and two points between. A single reading in the middle hides a taper that comes from tool wear or thermal drift. Record the readings and compare them to the drawing tolerance, which for our shop is typically ±0.005 mm on critical walls.
If the wall is out of tolerance after finishing, do not take a heavy corrective pass. Take 0.01–0.02 mm at a time with a sharp tool and check after each pass. Thin walls move in small increments, and a heavy pass will push the error past the tolerance in the other direction.
Step-by-step process for thin-wall parts
- 11. Check wall thickness and length ratioMeasure the wall and its unsupported length. If length ÷ thickness is above 10, plan extra support and expect to take two finishing passes instead of one.
- 22. Choose stress-relieved stockFor 7075 and 2024, ask for stress-relieved plate. For 6061, standard stock is usually fine below 2 mm wall thickness.
- 33. Set up with the wall supportedUse soft jaws, a filler, or a sacrificial web. Confirm the wall cannot move more than 0.01 mm when you push it by hand before cutting.
- 44. Rough with 0.3–0.5 mm stock on the wallUse a 12–16 mm end mill, 1,500–2,500 rpm in aluminium, 0.10–0.15 mm/tooth, 30–40% radial engagement. Leave the wall thick.
- 55. Semi-finish to 0.1–0.15 mm stockUse a 8–10 mm end mill, climb milling, 5–8% radial engagement for the wall pass. Check the wall with a micrometer before finishing.
- 66. Finish the wall lastUse a sharp, coated end mill at 0.05–0.10 mm radial depth, 0.15–0.25 mm axial depth, and 0.02–0.05 mm/tooth. Keep the feed constant through the whole wall.
- 77. Measure in the same setupMeasure the wall before unclamping. If it is oversize, take one more 0.02–0.03 mm pass. Do not unclamp and re-clamp to correct it.
- 88. Stress-relieve before the final pass if neededFor walls under 0.8 mm, run a light 0.02 mm pass, let the part sit for 30 minutes, then take the final pass.
Wall thickness and recommended finishing strategy
Use these ranges as a starting point, then adjust to the part geometry.
| Wall thickness | Finishing radial depth | Support method | Notes |
|---|---|---|---|
| Above 2.0 mm | 0.20–0.30 mm | Standard vise | Treat as a normal finishing pass |
| 1.0–2.0 mm | 0.10–0.15 mm | Soft jaws or web | Climb mill, keep the feed constant |
| 0.5–1.0 mm | 0.05–0.10 mm | Filler or full support | Two light passes, measure between them |
| 0.3–0.5 mm | 0.02–0.05 mm | Filler plus web | Finish last, air blast preferred |
| Below 0.3 mm | 0.01–0.03 mm | Full encapsulation | Expect spring-back, plan a spring pass |
The short version
Support the wall, rough it thick, finish it light, and measure before you unclamp. If your part has a wall under 1 mm, send the drawing and we will tell you whether it needs a filler, a web, or a different setup.
Thin-wall machining questions
What wall thickness counts as thin-walled?
In practice, a wall is thin when its unsupported length is more than 10 times its thickness. A 1 mm wall that is 30 mm long behaves like a thin wall. A 3 mm wall that is 20 mm long usually does not.
The material matters too. A 1 mm aluminium wall deflects more than a 1 mm steel wall under the same cut, so the ratio is a starting point, not a fixed rule.
Can thin walls be machined on a three-axis machine?
Yes, if the wall is accessible from one direction and the fixture supports it. Most thin-wall housings can be roughed on a three-axis machine and finished on the same setup.
Five-axis machines help when the wall has a curved profile or when you need to approach it from an angle to keep the tool engaged. We run thin-wall work on both, and the choice usually comes down to geometry, not wall thickness.
Why does the wall measure oversize after machining?
The wall springs back after the cutter passes. The tool pushes the wall away, cuts a smaller depth than programmed, and the wall returns to a position that leaves extra material. This shows up as an oversize wall.
The fix is to reduce radial depth and use climb milling, so the force goes into the support. A spring pass at 0.02 mm radial depth often removes the last 0.03–0.05 mm of oversize.
Should I use coolant on thin aluminium walls?
Air blast is usually better. Flood coolant cools one side of the wall faster than the other and creates a thermal gradient that warps the wall. Air blast clears chips and keeps the temperature more even.
On deep pockets where chip evacuation is difficult, use a mist or a high-pressure air blast aimed at the cut zone. Flood coolant is fine on thicker walls above 2 mm.
How do you hold a part with a 0.5 mm wall?
Fill the pocket with a low-melt wax or machinable resin, then machine the wall to final thickness. The filler takes the radial load and the wall does not move.
After machining, melt or dissolve the filler. This method works well on closed pockets. For open walls, use a profiled soft jaw or a vacuum fixture with a full gasket seal.
What tolerance can be held on a thin wall?
On a supported wall above 0.8 mm in aluminium, ±0.005 mm is achievable with a light finishing pass and in-process measurement. Below 0.5 mm, holding ±0.01 mm is more realistic unless the wall is fully encapsulated.
The tolerance you can hold depends on the support and the measurement method as much as the machine. Tell us the wall thickness and the tolerance on the drawing, and we will confirm what is practical before quoting.
Send us your thin-wall part
Upload a STEP file and we will return a DFM analysis and a quote within 12 hours. No minimum order quantity, from one prototype to a 10,000-part run.
12-hour quote100% inspectionNo minimum order
More from GreatLight
We publish setup notes, tooling trials and inspection data from the factory floor.
