Gear Processing Technology and Methods
This guide walks through gear processing technology and methods the way a process engineer plans a job: blank prep, tooth cutting, heat treatment, finishing, inspection. It is written for design and manufacturing engineers who need to pick a route and set real numbers. After reading, you can judge which method fits a given gear and where it will fail.
In this article
- 1
- 2
- 3
- 4
- 5
- 6
- 7
- 8
- 9
Key takeaways
What gear processing technology and methods actually control
A gear drawing carries three things that decide the process: module, accuracy grade, and material condition. Module sets the tooth size and therefore the tool and the machine. The grade, usually written to ISO 1328 or AGMA, sets how much profile and lead error the tooth may carry. Material condition decides whether you cut soft, cut then harden, or harden then grind.
If any one of the three is missing, the route is a guess. A module 3 spur gear in 1045 at grade 7 is a milling or hobbing job. The same size in 20MnCr5, case hardened to 58 HRC at grade 6, needs hobbing, heat treatment, and then grinding. Same shape, two very different shops.
Gear processing technology and methods are therefore not a menu of machines. They are a sequence chosen backwards from the finished tooth. Start at the inspection report you promised the customer, then walk back to the last operation that can produce it.
- 1ModuleTool size and cut depth; below 1 mm the tool gets fragile.
- 2GradeISO 1328 grade 6–9 covers most industrial gears.
- 3ConditionSoft, through hardened, or case hardened changes everything.
Blank preparation before any tooth is cut
Turn the blank to the outside diameter, bore, and both faces in one setup if the part allows it. The bore is the datum for every later operation, so its roundness and its squareness to the face matter more than its size. A bore that is 0.02 mm out of round will show up as lead error on every tooth.
For a gear that will be hardened, leave grinding stock on the bore and faces. A common allowance is 0.3–0.5 mm on diameter for the bore and 0.1–0.2 mm per face. For a soft gear finished by cutting only, hold the bore to H7 and the face runout under 0.01 mm.
Clamping is where most first-article failures start. Cutting a gear on a three-jaw chuck with soft jaws that were bored at a different diameter will distort the ring. Bore the jaws on the machine at the same clamping pressure you will use for the run, then check runout before the first tooth.
On our 127 CNC machines, blank turning and tooth cutting often run on the same mill-turn center, which removes one re-chucking step. That is worth doing whenever the gear is small enough for the machine envelope.
- 1Datum firstBore and face in one setup; everything else references them.
- 2Hardening stock0.3–0.5 mm on bore diameter, 0.1–0.2 mm per face.
- 3Soft jawsBore them on the machine at running clamp pressure.
Hobbing, shaping and milling: which one reaches the tooth
Hobbing is the default for external spur and helical gears. The hob is a rotating rack, and the generating motion produces the involute without a formed tool. It is fast, it handles module 1–8 comfortably, and it holds grade 8–9 straight off the machine. Add a good arbor and a rigid workholding and grade 7 is reachable.
Gear shaping uses a pinion cutter that reciprocates and rotates in mesh with the workpiece. It is slower than hobbing, but it cuts internal teeth and it reaches a shoulder or a flange that a hob cannot clear. If your gear has a hub that stands taller than the hob can run out, shaping is the answer.
Milling a gear tooth with a form cutter or a ball nose is the route for prototypes, repair work, and very large modules where no hob is on the shelf. It is a single-index operation, so the index table accuracy becomes tooth spacing accuracy. For one-off parts that is fine. For 500 pieces it is the wrong call.
For bevel and hypoid gears, the cutting method changes again: face milling or face hobbing on a dedicated bevel machine, with the cutter head tilted to generate the spiral angle. These are not jobs for a general milling center unless the quantity is one and the grade is loose.
- 1HobbingExternal spur and helical, module 1–8, best throughput.
- 2ShapingInternal teeth, shoulders, limited runout space.
- 3Form millingPrototypes and large modules; index accuracy rules.
Heat treatment and the distortion you have to plan for
Case carburizing at 900–950 °C followed by quenching gives a hard surface over a tough core, and it is the standard route for automotive and industrial gears. The problem is that the part moves. Bore diameter, pitch diameter and lead all shift during quench, and the shift is not identical from lot to lot.
Plan for it. A typical case-hardened gear loses 0.02–0.05 mm on the bore and picks up lead error that can push a grade 7 gear to grade 9. That is why the drawing usually specifies grinding after hardening, and why the pre-grind cut leaves 0.1–0.2 mm of stock on the flanks.
Through hardening is simpler. Quench and temper to 28–35 HRC and the distortion is smaller, but the tooth is still soft enough to finish by cutting. Many industrial gears stop here. Nitriding adds a hard skin at 500–560 °C with almost no distortion, which makes it attractive for large gears that will not fit a grinder.
Induction hardening of the tooth flanks is a fourth option. It is fast and it hardens only where you need it, but the transition zone between hard and soft can be a fatigue crack starter if the pattern is wrong. Ask for a hardness traverse, not just a surface reading.
- 1Carburize and quench58–62 HRC surface; expect 0.02–0.05 mm bore shrink.
- 2Through harden28–35 HRC; minimal distortion, cuttable after.
- 3Nitride500–560 °C, low distortion, good for large rings.
Grinding, honing and shaving for the final grade
Profile grinding and generating grinding remove the hardened skin and correct the distortion in one pass. This is where grade 5–7 and Ra 0.2–0.8 μm come from. Generating grinding is faster; profile grinding is more flexible on modifications and on small batches. Both need a dressed wheel and a stable room temperature.
Gear honing runs after grinding and polishes the flanks without changing the geometry much. It removes the grinding marks that act as stress risers and it can knock 1–2 μm off the surface. It does not fix a lead error. If the lead is wrong, go back to the grinder.
Gear shaving is a soft finishing operation that runs before heat treatment. It corrects profile and lead on an unhardened gear and it is cheap per piece at volume. The catch is that the shaving cutter is gear-specific and the lead time to make one is measured in weeks.
Lapping is still used for some bevel and worm gear sets, where two mating parts are run together with abrasive to build a matched contact pattern. It produces a pair, not an interchangeable part. Keep that in mind for spares planning.
- 1Generating grindingFast, grade 6–7, good for medium batches.
- 2Profile grindingFlexible, handles profile modification.
- 3HoningSurface improvement only; will not correct lead.
Inspection points that catch the failure early
Tooth thickness is the first number to check, because it sets backlash and it is easy to measure with a span micrometer or pins. Oversize teeth will not mesh in the assembly. Undersize teeth rattle and wear fast. Check it after every operation that touches the flank.
Profile and lead are next. A gear measuring center traces both and reports the deviation to the specified grade. If you do not have one, a functional check against a master gear gives you a pass or fail but not a number. Functional checks catch gross errors; they will not tell you that you are 3 μm from the limit.
Runout of the pitch circle relative to the bore is the third check, and it is the one that changes in heat treatment. A gear can have perfect profile and lead and still run noisy because the pitch circle is eccentric. Indicate it after hardening and again after grinding.
Finally, the contact pattern. Paint the flanks with marking compound, run the pair at the specified center distance under light load, and read the pattern. A pattern that sits at the toe or the heel tells you the mounting distance is wrong, not the tooth.
- 1Tooth thicknessSpan or pin measurement; controls backlash.
- 2Profile and leadGear measuring center; report to ISO 1328 grade.
- 3Pitch runoutIndicate after hardening and after grinding.
Step by step: cutting a case-hardened spur gear
- 11. Read the grade and the material togetherConfirm module from the drawing and check the material condition. If the drawing says 58 HRC and grade 6, you are in a grind-after-harden route. If it says grade 9 and 1045, you can stop at hobbing.
- 22. Turn the blank and hold the boreFace both sides, turn the outside diameter, and bore to H7 in one setup. Target face runout under 0.01 mm. Leave 0.3–0.5 mm on the bore diameter if hardening follows.
- 33. Set up the hob and check runoutMount the hob and indicate runout under 0.01 mm. Set the helix angle to the gear helix. Climb cut for better finish. Typical cutting speed 30–60 m/min for alloy steel.
- 44. Cut to pre-grind sizeLeave 0.1–0.2 mm of stock on the flanks. Check the first tooth for tooth thickness and profile before running the batch. Do not chase size with feed rate; adjust the depth of cut.
- 55. Deburr before heat treatmentA burr left on the tooth edge will harden and chip during grinding. Hand-file or brush the edges, then wash the part. Trapped chips in a blind bore can distort the quench.
- 66. Carburize, quench and temperCase depth is usually 0.6–1.0 mm for module 3–5. Expect the bore to shrink and the lead to move. Measure a sample after heat treatment, not the whole lot.
- 77. Grind the bore and the flanksGrind the bore first; it is the datum for flank grinding. Then grind profile and lead to the drawing grade. Keep coolant clean and let the part cool before measuring.
- 88. Inspect and reportCheck tooth thickness, profile, lead, and runout on a gear measuring center. Check the contact pattern with marking compound at the specified center distance. Reports on request.
Gear cutting method selection by case
Choose the method from the tooth geometry, the grade, and the batch size.
| Method | Reaches | Typical grade | Best for |
|---|---|---|---|
| Hobbing | External spur and helical | 8–9 as cut | Volume runs and general gears |
| Gear shaping | Internal and near-shoulder | 8–9 as cut | Internal rings and blind spaces |
| Form milling | External, any module | 10–11 | One-off prototypes and repair |
| Generating grinding | Hardened external | 6–7 | Hardened gears at volume |
| Profile grinding | Hardened external | 5–6 | Modified profiles, small batches |
| Gear shaving | Soft external | 6–7 | High volume before hardening |
| Bevel face milling | Bevel and hypoid | 7–9 | Bevel sets on dedicated machines |
Pick the route from the grade, not from the machine list
If the gear is soft and grade 9 is enough, hob it and ship it. If it is case hardened and grade 7 or better, plan for grinding from the first operation. Any route that skips that decision will fail at inspection.
Common questions
Can a CNC milling center cut a usable gear?
Yes, for prototypes and repair parts. A ball nose cutter on a 3-axis or 4-axis mill can mill a spur or helical tooth by indexing the part. The involute is approximated by the tool path, so the flank is not a true involute, and the surface carries scallops.
That is acceptable for a one-off gear running at low speed. It is not acceptable for a grade 7 gear at 3,000 rpm. For those, use hobbing or shaping, then grind if hardened.
How much stock should I leave for grinding after heat treatment?
A common range is 0.1–0.2 mm on the tooth flanks and 0.3–0.5 mm on the bore diameter. The bore allowance covers the shrink that comes with quenching.
Thin rings and gears with a large bore-to-diameter ratio move more. If the ring is thin, take the upper end of the range and measure a heat-treatment sample before committing the batch.
What causes a gear to pass inspection but run noisy?
Usually pitch runout or a lead error that the inspection plan did not cover. A gear can be within tooth thickness and profile tolerance and still have an eccentric pitch circle.
The other common cause is the mounting. A gear pressed onto a shaft with a poor fit will run with a wobble that no tooth measurement shows. Check the shaft fit and the face runout of the shoulder.
Is nitriding a substitute for carburizing?
Only where the load is moderate. Nitriding gives a hard skin at 500–560 °C with very little distortion, which is why it suits large gears that will not fit a grinder.
The case is thinner than a carburized case, so it does not carry the same bending stress at the tooth root. For high-torque gears, carburize and grind.
How do you hold a gear without distorting the bore?
Bore the soft jaws on the machine at the clamping pressure you will use for the run. For thin rings, use a face driver or a expanding mandrel instead of three-point clamping.
After cutting, check the bore roundness with the part still clamped and again after release. If it changes, the clamping is the problem, not the cutting.
What information do you need to quote a gear?
Send the drawing with module, number of teeth, pressure angle, helix angle, accuracy grade, material, and heat treatment. Add the bore and face tolerances and any required surface finish.
If the drawing is incomplete, tell us the application and the load. We can suggest a grade and a route, and return a quotation with free DFM analysis within 12 hours.
Send the gear drawing and get a route, not just a price
We review the drawing, flag the grade and heat-treatment risks, and return a quotation with DFM feedback within 12 hours. From one prototype to 10,000+ part runs, no minimum order quantity.
12-hour quote100% inspectionNDA on request±0.005 mm
More from GreatLight
We publish setup notes, tooling trials and inspection data from the factory floor.
