4 Axis CNC Applications: Where the Rotary Table Earns Its Keep

A standard 3-axis mill moves the tool in X, Y and Z. Everything the tool reaches has to face upward, so any feature on the other four sides of a block needs a second or third setup. Each extra setup costs time and adds a datum shift that shows up in the tolerance stack.

A fourth axis is a rotary table or indexer mounted on the machine bed, turning the part around the X axis. That axis is called A. The part rotates instead of the tool, so a face that pointed sideways can now be presented to the cutter by indexing the table. Work that needed three setups can often be done in one.

The spindle still approaches from one direction. That is the key difference from 5-axis, where the tool tilts as well. With 4 axes, the part indexes to a new angle and then the cut runs in the usual X, Y, Z envelope. Simple to program, simple to verify.

That single-fixture approach matters most for parts with features on several faces. A manifold with ports at 0°, 90° and 180°, a shaft with milled flats and cross-holes, a bracket with drilled faces on four sides. All of these are natural 4 axis CNC applications because the geometry repeats around an axis.

• 1
  Rotation, not tiltThe A-axis indexes the part. The tool stays perpendicular to the work.
• 2
  One datumFeatures on multiple faces share a single setup and a single zero point.
• 3
  Positional indexingCuts happen at fixed angles, so the table can lock before each pass.

The geometry that pays off is anything with features wrapped around one axis. Think of a part you would describe as a cylinder, a bar or a prismatic block with repeated faces. If the drawing has a rotation axis and features at multiple angles around it, the fourth axis is doing useful work.

Shafts and spools are the classic case. Journals, keyways, cross-drilled oil holes and milled flats sit at different angles around the centerline. Turned on a lathe and then milled, this part needs two machines and a re-chuck. A mill-turn center or a 4-axis mill with the part held in a chuck can do it in one cycle.

Prismatic housings and manifolds are the second family. Fluid ports, sensor bosses and bolt patterns land on several faces of a rectangular block. Indexing the table 90° at a time presents each face to the cutter without removing the part. The bolt-hole pattern on the top and the port on the side keep the same datum.

The third family is brackets and mounts with angled or radial features. A pair of ears with bores on a common axis, a mounting flange with slots at every 60°, a hinge body with a cross-bore. These parts are awkward in a vise because the angle has to be set by hand. On a rotary table the angle is just a number in the program.

• 1
  Shafts and spoolsKeyways, flats and cross-holes around one centerline.
• 2
  Manifolds and housingsPorts and bolt patterns on three or four faces.
• 3
  Brackets and flangesBores and slots at fixed angular positions.
• 4
  Cams and index platesProfiles that repeat at equal angles around a bore.

The measurable win is setup count. Going from three fixtures to one removes two chances to introduce a locating error. Positional tolerance between faces is then set by the rotary table, not by how carefully an operator re-clamped the block. We hold ±0.005 mm on critical features and inspect 100% of parts before shipment.

Cycle time also drops, but not as much as people expect. The cutting itself takes about the same time. What disappears is the handling between operations: unclamping, blowing chips, re-zeroing, proving the new offset. On a five-face part that can be 20 to 40 minutes of non-cutting time per piece. On a one-off it hardly matters. On a 500-piece run it dominates.

There is a stiffness penalty to respect. The rotary table and chuck add overhang, so a long part hanging out of a three-jaw chuck will chatter where the same part held in a vise would not. Keep the work close to the table, use a tailstock when the part allows it, and take lighter radial cuts on slender sections.

Positioning accuracy of the table matters more than its speed. A table that indexes to ±5 arc-seconds puts a hole on a 100 mm radius within about 0.0024 mm of true position. That is usually finer than the drawing needs. Rotary speed only earns money on parts with many short indexes.

• 1
  Fewer datumsEach removed setup deletes one source of stack-up error.
• 2
  Hidden timeRe-clamping and re-zeroing often cost more than the cut.
• 3
  Rigidity limitChuck overhang reduces the depth of cut on slender parts.

Aluminium is the easy case. 6061-T6 and 7075 cut fast on a rotary table, and the low cutting force means a small chuck or a between-centers setup holds fine. Stainless 304 and 17-4PH need more attention: the material work-hardens, so keep the feed per tooth up and avoid dwelling at the index position.

Titanium TC4 (Ti-6Al-4V) and Inconel are where the fourth axis earns its cost. These alloys are slow to cut, so any handling time saved is a large share of total cost. They also cut hot, and keeping the part on one fixture means the thermal state stays consistent from the first feature to the last.

Fixtures decide whether the job runs well. Options we use include a three-jaw chuck for round stock, a 5C collet block for small parts, a tombstone with two or four part stations, and a tailstock for long shafts. A tombstone is the usual answer for a production run: load four parts, cut four parts, index once.

On the programming side, the CAM post must output the A-axis correctly. For 3+1 work the table indexes and locks, and the cut runs as a plain 2.5D or 3D path. That is the safe route and what we use for most jobs. Simultaneous 4-axis motion is reserved for helical slots and wrapped contours, where the table turns while the tool cuts. It is harder to verify and rarely needed.

Our 12 four-axis mills run alongside 16 simultaneous 5-axis centers and 27 three-axis machines, so we route work to the machine that fits rather than forcing every part onto the newest equipment. A Ø400 mm rotary table covers most of the shaft and housing work we see.

• 1
  3+1 indexingTable locks, then cuts. Easier to verify and the default choice.
• 2
  Simultaneous 4-axisTable turns during the cut. Needed for wrapped slots and helices.
• 3
  Tombstone fixturesMultiple part stations cut handling time on production runs.
• 4
  Tailstock supportControls deflection on long shafts held in a chuck.

The fourth axis does not tilt the tool, and that is a hard limit. A face that is not perpendicular to the A-axis at some index position cannot be reached. If the part has a compound angle, a deep undercut or a wall that leans away from the cutter, no amount of table rotation will fix it. That work belongs on a 5-axis machine.

Contoured surfaces are the second boundary. Impeller blades, turbine vanes and free-form mould cavities need the tool to follow a surface in three dimensions while the part turns. A 4-axis machine can approximate some of this, but the tool marks show and hand polishing follows. If the surface is functional rather than cosmetic, go 5-axis.

Single-face parts are the third case. A plate with pockets and holes all on one side is a 3-axis job. Adding a rotary table only adds setup time and reduces rigidity. We push those parts to a 3-axis machine on purpose.

Part size also decides. Our 4-axis envelope suits parts up to a few hundred millimetres in diameter on the table. Beyond that, the part weight and the swing become the constraint, and a large-travel machine with a different setup is the better route.

• 1
  Compound anglesTool tilt is required. Route to 5-axis.
• 2
  Free-form surfacesSimultaneous 3D contouring beats indexing.
• 3
  One-face platesA 3-axis machine is faster and more rigid.